【讨论】五軸後處理的問題 雙工作檯

游客，本帖隐藏的内容需要积分高于 20 才可浏览，您当前积分为 0

sinderal wrote:
注意: B軸是手動擺的旋盤...  
   
  這樣的程序會整死 我客戶的....  
   
  分析一下那個要鑚孔的面是斜幾度? Yeager再想想...

喔!!小弟再改過....
其實也好辦,我在Machine Control加一個"LOCK AXIS"的PP Word,鎖住B軸在20度,其他還是交給PP處理.系統會自動對其他的數值(XYZBR...)作補償
  
Origional:
N0010 G40 G17 G90 G71
N0011 G91 G28 Z0.0
N0012 T00 M06
N0013 G00 G90 X27.752 Y548.427 B-20.004 C280.954 S0 M03
N0014 G43 Z117.527 H00
N0015 G81 X22.391 Y548.427 Z98.801 R102.801 F250.
N0016 X22.543 Y549.02 Z98.745 C274.639 R102.745
N0017 X22.572 Y550. Z98.734 B-20. C269.999 R102.734
N0018 X22.543 Y550.981 Z98.745 B-20.004 C265.36 R102.745
N0019 X22.39 Y551.573 Z98.801 C259.041 R102.801
N0020 X22.159 Y550.652 Z98.885 B-20.008 C246.299 R102.885
N0021 X22.165 Y549.745 Z98.889 B-20.036 C233.747 R102.889
N0022 X22.249 Y548.797 Z98.85 B-19.995 C220.972 R102.85
N0023 X22.295 Y547.901 Z98.791 B-19.821 C208.154 R102.791
N0024 X22.944 Y547.133 Z98.574 B-19.895 C195.453 R102.574
N0025 X23.732 Y546.918 Z98.318 B-20.032 C184.776 R102.318
:
  
After adding Lock Axis:
%
N0010 G40 G17 G90 G71
N0011 G91 G28 Z0.0
N0012 T00 M06
N0013 G00 G90 X32.57 Y548.427 B20. C280.954 S0 M03
N0014 G43 Z95.569 H00
N0015 G81 X17.069 Y548.427 Z84.437 R88.437 F250.
N0016 X17.149 Y549.02 Z84.297 C274.639 R88.297
N0017 X17.165 Y550. Z84.271 C269.999 R88.271
N0018 X17.149 Y550.981 Z84.297 C265.36 R88.297
N0019 X17.068 Y551.573 Z84.438 C259.041 R88.438
N0020 X16.944 Y550.652 Z84.65 C246.299 R88.65
N0021 Y549.745 Z84.641 C233.747 R88.641
N0022 X16.994 Y548.797 Z84.569 C220.972 R88.569
N0023 X17.035 Y547.901 Z84.546 C208.154 R88.546
N0024 X17.375 Y547.133 Z83.941 C195.453 R87.941
N0025 X17.778 Y546.918 Z83.197 C184.776 R87.197
:

工件怎麼擺啊? 怎麼打旋盤的角度? 來個示意圖............

o.o  師傅  
能不能不要機分這ㄇ高 o.o
我很想看捏  

sinderal wrote:
工件怎麼擺啊? 怎麼打旋盤的角度? 來個示意圖............

老哥您這個B軸到底長怎樣呢??是掛在主軸(Head Table) or C軸轉盤(Dual Table)??
工件怎麼擺??試過兩種形式的PP,Lock Axis的指令都可以用,所以工件的夾持與一般五軸加工時的方式是一樣的!!
實在不了解老哥您的意思!?!?!?

Yeager wrote:
   
  老哥您這個B軸到底長怎樣呢??是掛在主軸(Head Table) or C軸轉盤(Dual Table)??  
  工件怎麼擺??試過兩種形式的PP,Lock Axis的指令都可以用,所以工件的夾持與一般五軸加工時的方式是一樣的!!  
  實在不了解老哥您的意思!?!?!?

  
有些人第一次遇到, 不了解啊....
主軸擺動固定的話, 先打主軸角度, 將程序裡的B20部分刪掉..
手動工作檯的話, 也是先將工作台打到B20, 將程序裡的B20部分刪掉..
  
如果,沒有Dynamic Offset的功能, 怎麼辦?

原來如此,了解老哥您的東東了!!!有空再好好想想..............

车铣线

THANK YOU VERY MUCH....

受教了，多学习一下。