做的满不错嘛, 这其实是PRO/NC做多轴最基本的步骤.
需要补充一点的是, 在参数表中, 要根据具体情况设定FIX_OFFSET_REG(工件坐标系)为54或55, 56..., 这样, POST后的程序才有G54或G55...
另外, 在所有侧头程序的后面, 要用CUSTOMIZE(客户化)插入一个沿OPERATION(操作)坐标戏Z轴的刀具运动, 否则不安全.
下面是你的NCL文件的POST结果:
%
(Date:11/14/05 Time:15:39:02)
G98G80G90G49G17
( / MFG0002)
T1 M06
S400 M03
G18 G55 X175. Y100.
G0 Y100. H1
Z-575.
G18
G81 Y-3.906 R5. F25.
Z-650.
X850.
Z-575.
X1100. Z-186.
Z-126.
G80
G0 X1424.77 Y100.
Z-157.23
G81 Y-43.906 R5. F25.
X1439.01 Z-210.36
X1453.25 Z-263.49
X1560. Z-121.
X1574.24 Z-174.13
X1588.48 Z-227.26
G80
G0 Z-196.
X1635. Y100.
G81 Y-3.906 R5. F25.
X1685.
X1835. Z-315.
Z-440.
Z-590.
X2213.
Z-440.
Z-315.
X1995. Z-134.
X1935.
G80
M05
M30
%
下面是偶们测试其他NCL文件的POST结果:
%
(Date:11/14/05 Time:15:37:35)
G98G80G90G49G17
( / LL)
T1 M06
S2500 M03
G17 G54 X-7. Y0.
G0 X-7. Y0. Z0. H1
Z5.
G0 Z.25
G1 Z0. F10.
X1.
Y.6951
X-7.
Y1.3901
X1.
Y2.0852
X-7.
Y2.7802
X1.
G0 Z5.
M05
T2 M06
S2500 M03
G18 G55 X-3.124 Y-5.
Y-5. H2
Z-2.75
Y-.15
G1 Y0. F10.
G18
G1 G41 X-2.624 D1
G2 X-2.624 Z-2.75 I1.124 K0.
G1 G40 X-3.124
G0 Y-5.
Z5.
M05
T3 M06
S2500 M03
G18 G55 X-5.664 Y-5.
Y-5. H3
Z-5.265
G81 Y.3751 R-.15 F10.
X-3.164
X-.664
Z-.235
X-3.164
X-5.664
G80
G0 Y-5.
Z5.
M05
T2 M06
S2500 M03
G19 G56 X5. Y1.0979
X5. H2
Z-3.2732
X-.35
G1 X-.5 F10.
G19
G1 G41 Y1.5979 D1
Z-2.75
G3 Y1.0579 J-.27 K0.
G1 Z-3.8916
G3 Y1.5979 J.27 K0.
G1 Z-3.2732
G40 Y1.0979
G0 X5.
Z5.
M05
M30
%
晚上再把后处理器PM给你. |