這裡太冷清了,学不到什広東西

你可以改一点的，  如果不懂德文， 将Language的项目改为ENG就变成英文了

RAY版主謝謝您的提醒,難怪檔頭的英文看不懂
小弟已經更改好了,再次的感謝您的指點
0 BEGIN PGM Basis_01a_6 MM
1 BLK FORM 0.1 Z X-90 Y-131.1989 Z-84.6913
2 BLK FORM 0.2 X90 Y128.8011 Z0.3087
3 ; B_mode_5X: 2
4 ;
5 ; --- TOOLLIST ---
6 ; T2 - 圓鼻刀 - D20R2
7 ;
8 * - OPERATION 2
9 ; E O M
10 M127 ; SHORTER PATH TRAVERSE OFF
11 M129 ; TCPM OFF
12 ; * RESET WORKING PLANE *
13 LBL 1
14 CYCL DEF 7.0 DATUM SHIFT
15 CYCL DEF 7.1 X+0
16 CYCL DEF 7.2 Y+0
17 CYCL DEF 7.3 Z+0
18 PLANE RESET STAY
19 LBL 0
20 ---> [1]
21 L Z0 R0 F MAX M92
22 L X-20 Y-320 R0 F MAX M92
23 TOOL CALL 2 Z S2000 DL-2
24 CYCL DEF 247 DATUM SETTING~
  Q339= 0 DATUM NUMBER~

c24229096 发表于 2009-8-9 09:25
bbzzcl您好
我佷好奇怎麼沒有看到程式內的TA_值呢,五軸連動加工如果使用Heidenhain控制器
因為那是控制Ｂ軸及Ｃ軸連動時的順暢与否,
其实加工所產生的問題比軟体還難搞,

呵呵，只是没有贴完，这是另一个：
0 BEGIN PGM 5A-20-2B.H MM
1 BLK FORM 0.1 Z X-200 Y-100 Z-50
2 BLK FORM 0.2 X200 Y100 Z0
3 PLANE RESET STAY
4 M140 MB MAX
5 ;(D: 20 R: 10)
6 ;(TOOL COMMENT: 无备注)
7 TOOL CALL 13 Z S4000
8 L B0 R0 F6666.
9 L IX-100 F6666.
10 M03
11 ;(PROCEDURE: 高级5轴-航空铣 #7: NO TEXT)
12 M128
13 L X-97.739 Y-88.367 Z159 C2.172 B-29.854 F4000.
14 M08
15 L X-.704 Y-84.686 Z-10.182
16 L X1.783 Y-84.592 Z-14.519 F1500.
17 L X1.936 Y-84.038 Z-14.785
18 L X2.137 Y-83.24 Z-15.135
19 L X2.319 Y-82.424 Z-15.454
20 L X2.484 Y-81.593 Z-15.74
21 L X2.629 Y-80.748 Z-15.994
22 L X2.756 Y-79.891 Z-16.215
23 L X2.864 Y-79.023 Z-16.403
24 L X2.952 Y-78.147 Z-16.557
25 L X3.021 Y-77.263 Z-16.676
26 L X3.069 Y-76.374 Z-16.762
27 L X3.099 Y-75.482 Z-16.812
28 L X3.11 Y-74.587 Z-16.833
29 L Y-74.668 C2.094 B-29.853
30 L X3.111 Y-75.214 C1.564 B-29.846
31 L Y-75.76 Z-16.834 C1.034 B-29.84
32 L Y-76.306 C0.504 B-29.837
33 L Y-76.852 C-0.027 B-29.836
34 L Y-77.398 C-0.557 B-29.838
35 L Y-77.944 C-1.087 B-29.841
36 L Y-78.49 Z-16.833 C-1.618 B-29.846

大大您的程式檔頭好像少了座標(CYCL DEF 247 ,或者１９)
直接執行程弍Ｍ128那工件原點在那裡呢
這是我転出來的比較一下
0 BEGIN PGM AAA-01 MM
1 BLK FORM 0.1 Z X-11.4466 Y-23.5516 Z-5.421
2 BLK FORM 0.2 X23.0646 Y12.1793 Z16.703
3 ; B_mode_5X: 2
4 ;
5 ; --- TOOLLIST ---
6 ; T1 - 球頭刀 - D2
7 ;
8 * - OPERATION 1
9 ; YAY M
10 M127 ; SHORTER PATH TRAVERSE OFF
11 M129 ; TCPM OFF
12 ; * RESET WORKING PLANE *
13 LBL 1
14 CYCL DEF 7.0 DATUM SHIFT
15 CYCL DEF 7.1 X+0
16 CYCL DEF 7.2 Y+0
17 CYCL DEF 7.3 Z+0
18 PLANE RESET STAY
19 LBL 0
20 ---> [1]
21 L Z0 R0 F MAX M92
22 L X-20 Y-320 R0 F MAX M92
23 TOOL CALL 1 Z S2000 DL-1
24 CYCL DEF 247 DATUM SETTING~
  Q339= 0 DATUM NUMBER~
25 ---> [1]
26 L Z0 R0 F MAX M92
27 L X-20 Y-320 R0 F MAX M92
28 ---> [1]
29 L M126 ; SHORTER PATH TRAVERSE ON
30 M25
31 M26
32 L B68.83 C42.127 R0 F MAX M13
33 L M128 ; TCPM ON
34 L X10.4651 Y12.1793 R0 F MAX
35 L Z20 R0 F MAX
36 CYCL DEF 32.0 TOLERANCE
37 CYCL DEF 32.1 T0.05
38 CYCL DEF 32.2 HSC-MODE:1
39 L Z16.2429 R0 F MAX
40 L X7.0071 Y9.0517 Z14.4372 F200
41 L X6.8192 Y8.8381 Z14.3213
42 L X6.7958 Y8.5934 Z14.218
43 L X6.899 Y8.3801 Z14.147
44 L X7.0463 Y8.2425 Z14.1137
45 L X7.17 Y8.1338 Z14.0884
46 L X7.2938 Y8.025 Z14.0632
47 L X7.4176 Y7.9163 Z14.0379
48 L X7.5413 Y7.8076 Z14.0127
49 L X7.6651 Y7.6988 Z13.9874
50 L X7.8803 Y7.5098 Z13.9435 B68.727 C40.628
51 L X8.0954 Y7.3208 Z13.8996 B68.638 C39.127
52 L X8.2781 Y7.1526 Z13.8555 B68.592 C37.222

后置里没有设定坐标系，都是手动加的，因为刚接触Heidenhain,不是很完善，后来已经加上了，您看现在的，这是今天改的：
0 BEGIN PGM D6-1#-J-3.H MM
1 BLK FORM 0.1 Z X-200 Y-100 Z-50
2 BLK FORM 0.2 X200 Y100 Z0
3 PLANE RESET STAY
4 M140 MB MAX
5 ;(D: 6 R: 3)
6 ;(TOOL COMMENT: 无备注)
7 TOOL CALL 9 Z S8000
8 CYCL DEF 247 DATUM SETTING~Q339=+1 ; DATUM NUMBER
9 L B0 R0 F6666.
10 L X-400 F6666.
11 M03
12 ;(PROCEDURE: 高级5轴-航空铣 #46: D6-1#-J-3)
13 M128
14 L X85.819 Y-130.851 Z159 C-261.871 B-41.693 F4000.
15 M08
16 L Z131.549
17 L X67.478 Y-2.452 Z-14.061
18 L X67.008 Y.841 Z-17.794 F2500.
19 L X66.999 Y.31 Z-17.801 C-261.901 B-41.495
20 L X66.986 Y-.221 Z-17.808 C-261.927 B-41.295
21 L X66.969 Y-.752 Z-17.815 C-261.95 B-41.095
22 L X66.948 Y-1.282 Z-17.822 C-261.969 B-40.894

PM600
0 BEGIN PGM T6 5X MB Point Milling_2 MM
1 BLK FORM 0.1 Z X-48 Y-48 Z-63.074
2 BLK FORM 0.2 X48 Y48 Z-9.059
3 ; A_mode_5X: 2
4 ; A_mode_frame: 2
5 ;
6 ; --- TOOLLIST ---
7 ; T6 - 球磨刀 - D2.5
8 ;
9 *- OPERATION 2
10 ;COAE   
11 M127 ; SHORTER PATH TRAVERSE OF ROTARY AXES OFF
12 M129 ; TCPM OFF
13 CALL LBL 1
14 L M140 MB MAX
15 L X-150 Y298 R0 F MAX M92
16 L A0 R0 F MAX
17 TOOL CALL 6 Z S9000 DL-1.25
18 L M140 MB MAX
19 L X-150 Y298 R0 F MAX M92
20 FN 02=300 ; FEEDRATE XY
21 FN 03=0 ; FEEDRATE Z
22 CYCL DEF 32.0 TOLERANCE
23 CYCL DEF 32.1 T0.05
25 L M126 ; SHORTER PATH TRAVERSE OF ROTARY AXES ON
26 L A69.774 C269.477 R0 F MAX M13
27 L X-300 Y180 R0 F MAX M92
28 L M128 F10000 ; TCPM ON
29 L X-40.577 Y0.111 Z50 R0 F MAX
30 L Z-7.578 R0 F MAX
31 L X-38.701 Y0.094 Z-8.269 FQ2
32 L X-38.419 Y0.091 Z-8.373
33 L X-38.339 Z-8.403
34 L X-37.304 Y0.034 Z-8.79
35 L X-37.116 Y-0.088 Z-8.875
36 L X-37.092 Y-0.188 Z-8.896
37 L X-37.083 Y-0.67 Z-8.962 A69.685 C271.817
38 L X-37.055 Y-1.249 Z-9.203 A69.341 C274.476
39 L X-36.777 Y-4.292 Z-11.02 A66.656 C283.243
40 L X-36.435 Y-6.636 Z-12.501 A64.563 C288.16
41 L X-35.953 Y-8.912 Z-13.97 A62.435 C292.51
42 L X-35.23 Y-11.458 Z-15.697 A59.938 C297.139
43 L X-34.394 Y-13.797 Z-17.439 A57.426 C301.286
44 L X-33.42 Y-16.107 Z-19.301 A54.896 C305.321
45 L X-32.403 Y-18.333 Z-21.317 A51.981 C309.157

3+2，加工
0 BEGIN PGM 五面体 MM
1 BLK FORM 0.1 Z X350 Y-190 Z-340
2 BLK FORM 0.2 X501 Y190 Z-160
3 ; A_mode_5X: 2
4 ; A_mode_frame: 2
5 ;
6 ; --- TOOLLIST ---
7 ; T4 - 圆鼻铣刀 - D20R0.01
8 ;
9 *- OPERATION 4
10 ;O  CI   
11 M127 ; SHORTER PATH TRAVERSE OF ROTARY AXES OFF
12 M129 ; TCPM OFF
13 CALL LBL 1
14 L M140 MB MAX
15 L X-150 Y298 R0 F MAX M92
16 L A0 R0 F MAX
17 TOOL CALL 4 Z S10000
18 L M140 MB MAX
19 L X-150 Y298 R0 F MAX M92
20 FN 02=2000 ; FEEDRATE XY
21 FN 03=350 ; FEEDRATE Z
22 L A90 C90 R0 F MAX M126
23 CYCL DEF 7.0 DATUM SHIFT
24 CYCL DEF 7.1 #33
25 CYCL DEF 7.0 DATUM SHIFT
26 CYCL DEF 7.1 IX500
27 CYCL DEF 7.2 IY0
28 CYCL DEF 7.3 IZ-250
29 CYCL DEF 19.0 WORKPLANE
30 CYCL DEF 19.1 A90 C90 F3500
31 CYCL DEF 10.0 ROTATION
32 CYCL DEF 10.1 ROT 0
34 L X-4 Y-86 R0 F MAX M13
35 L Z50 R0 F MAX
36 L Z1 R0 F MAX
37 L Z0 FQ3
38 CC X0 Y-86
39 C X0 Y-90 DR+ FQ2
40 L X190 Z-6.786

没见过软件做到HM一样的效果。   
就算是M128全动， HM的后置也先做3+2定位的。 对机器五轴的认识， HM绝对是No#1.

CYCL DEF 32.0 TOLERANCE            
CYCL DEF 32.1 T0.020            
CYCL DEF 32.2 HSC-MODE:0            
L X-38.536 Y-46.097 R0 FMAX
L Z30. R0 FMAX
L Z3. R0 FMAX
L Z0.0 FQ4
L X-36.625 Y-44.484 RL
CC X-42. Y-40.
C X-35. Y-40. DR+ FQ4
L Y35.359 FQ1
CC X-30. Y35.359
C X-30. Y40.359 DR- FQ1
L X60.566
CC X60.566 Y35.359
C X65.566 Y35.359 DR- FQ1
L Y-40.
CC X60.566 Y-40.
C X60.566 Y-45. DR- FQ1
L X-30.
CC X-30. Y-40.
C X-35. Y-40. DR- FQ1
L Y-35.
CC X-42. Y-35.
C X-38. Y-29.255 DR+ FQ4
L R0
L X-40.269 Y-28.205 R0
L Z3.
L Z30. R0 FMAX
CYCL DEF 32.0 TOLERANCE         
CYCL DEF 32.1
*- PLANAR_MILL end
;
;
L M9
L M5
CALL LBL 1
L Z-2. R0 FMAX M91
L X-2. Y0.0 R0 FMAX M91
L B0 C0 R0 FMAX
;( TOTAL Machine Time =0.31 )
M2                                      
;( MAXX = 65.566 , MINX = -40.269 )
;( MAXY = 40.359 , MINY = -46.097 )
;( MAXZ = 30. , MINZ = 0. )
;( MAXB = 0. )
;( MINB = 0. )
END PGM post_M128 MM

在用的ug后处理