【分享】Surfcam Tips 小技巧

5.还是要手工连接端点，构成轮廓线。

給我SolidWorks的sldprt檔案...我做給你看

prt & Igs

自己按教程試試看 ....

现在对了，我知道其原理了。第9楼我方向选择错误。

Surfcam Multi-Speed
  
Edit your post processor to allow multiple RPM Speed codes for the same tool.  
Example : You have several pockets and counter-bores that you wish to do with the same tool but you would prefer to use several RPM speeds for the different features. In order to achieve this you must modify your post processors with 3 new lines of code.
   
First open the windows explorer and locate your Postform.m file. Normally it can be found in the C:\SURFCAM\Postlib\ directory. Double click the Postform.m file and it should open in a text editor. Scroll down until you get to the infeed section then type in the three lines shown in bright blue below. This must be done to each post in your postform.m file. ( It is always a good Idea to save a backup of your file before you edit it.)  
   
   
Infeed
G[Side] X[H] Y[V] D[DComp] F[FRate]
end
   
Upon [Speed]  
S[Speed]
End  
   
Outfeed  
G1 G40 X[H] Y[V]  
end

Posthaste Rotation Angles
  
Setting up Posthaste for correct Rotation Angle Output:  
There is a possibility of incorrect rotary angles being output with "CView Machining" (4 axis indexing of 2 axis toolpaths). The following provides a thorough look at the Posthaste and SURFCAM settings for proper rotational output.
  
   
   
   
  
--- Fact # 1 ---
  
The SET AXIS command in SURFCAM defines a vector that shows which direction the indexer is facing.  
  
   
  
Examples:  
  
(0,0,0) (1,0,0) indicates that the indexer is on the left end of the machine table (X-), facing towards the right (X+) end.
  
(0,0,0) (-1,0,0) (or [1,0,0] [0,0,0]) indicates that the indexer is on the RIGHT end of the machine table (X+), facing towards the LEFT (X-) end.  
  
NOTE: The latter is the "default" setup that most vertical machines use.
  
   
  
   
  
--- Fact # 2 ---
  
The INDEX statement in the post template (PostForm file) indicates which end of the table the indexer is on, which is the OPPOSITE way it is facing.
  
To set up SURFCAM and the post for the most common  4 axis setup (the latter of the above examples) you would use the following settings:  
  
In SURFCAM , SET AXIS should be (0,0,0) (-1,0,0) or an equivalent value such as (1,0,0) (0,0,0), which is typically facing to the left towards X-, on a standard vertical mill.  
  
In PostForm.m , use  INDEX X  to indicate that the indexer is on the X+ (right) end of the machine table, which means that it is facing left, matching the above “Set Axis” data.  
  
   
  
--- Fact # 3 ---
  
For consistent correct angle output, the SET AXIS data in SURFCAM must be describing the same rotary table orientation as the PostForm file. While SURFCAM’s vector indicates which direction the indexer is facing, the INDEX line in the template tells the post where the indexer is.  
  
Both areas describe the same data in 2 different ways. To make sure these 2 elements match, keep the following in mind when setting the SET AXIS and INDEX values.  
  
If the Set Axis vector is pointing towards X+, Use "Index X-".
  
If the Set Axis vector is pointing towards X-, Use "Index X".
  
NOTE: You must apply the same logic to "B axis" (typically horizontal mill) indexing - using INDEX Y or Y- accordingly.
  
If you need to reverse the sign to a positive or a negative on the rotary angle, use the MULT -1   modifier on the letter A or B. Do NOT just add or take away the “minus” on the INDEXline in the template.
  
The default SURFCAM installation has the SET AXIS data as follows in the configuration settings (Tools, Options, NC Defaults, 4 axis, Rotary Options) . For a typical "rotary table on the right" setup we would simply compensate for this by setting the post template to Index X-. Again, you can use the Mult -1 modifier if you need to reverse the sign on your rotary axis letter.  
  
  

2005 SolidWorks Associativity
  
One Button Transfer Utility:  
The "One Button" transfer utility is not required for associativity between SolidWorks and SURFCAM 2005. Opening a SolidWorks file directly in SURFCAM will make that file automatically associative. The "One Button" can still be used as an alternate means of associativity. There is a newer "One Button" utility on the SURFCAM web site for all "Sales Partners", under the category "SURFCAM".

How To Choose The Proper Lathe Tool:
  
There are two things to remember when choosing a lathe tool.  The default operation (cutting direction) of the tool and the default orientation (mounting angle) of the tool.  Both of these settings default the tool to the proper angle and cutting direction. These settings can be found by editing the tool.  The description of the tool by its naming convention usually implies the cutting direction and mounting angle, unless it has been previously edited.  Below are examples of the cutting directions and mounting angles.
  
   
   
   
  
DEFAULT OPERATION (cutting direction).  Blue indicates approach while green indicates cutting direction
  

DEFAULT ORIENTATION (mounting angle).  Editing the tool and typing in the desired angle can easily change the mounting angle.
  
NOTE: A negative opposite value can be used. Example: A -45 degrees can be used in place of 315 degrees.