UG NX 2.0 WHAT'S NEW

Highlight Line Analysis
What is it?
The Highlight Lines analysis lets you evaluate the aesthetic form of a model. There are two methods of generating Highlight Lines, reflection and projection.
  
Reflection recreates the way a simulated set of tube lights reflect at you when positioned in a fixed location. The reflection lines dynamically update as you rotate the model in the graphics window, allowing you to make crucial design decisions.

Projection maps a simulated set of tube lights to selected faces, but does not reproduce the reflections. This is useful for evaluating the consistency of shape in a set of faces, or for evaluating the geometric quality of surfaces by easily locating depressions in faces or discontinuities between faces.

Both the reflection and projection methods include options to create the lights uniformly, through selected points, or uniformly between two selected points.
  
Uniformly lets you define the number of lights and the spacing between them.
  
Through selected points lets you create Highlight Lines exactly at points of interest.
  
Between selected points lets you select two points that define a range. The number of lights you specified are then created between the selected points.
  
Why should I use it?
Highlight Line Analysis is an extremely useful tool for industrial designers creating aesthetic surfaces. During the creation of Class A surfaces the need arises to evaluate the way in which light flows across a set of faces or how faces will reflect light. This is a mandatory check of surface quality as well as a necessary set of tools for the creation of aesthetically correct surface form.  
  
Where do I find it?
Analyze Shape toolbar
  
Analysis-> Highlight Lines

Snip Surface
What is it?
The new Snip Surface function lets you break a surface at a specific point or snip off unneeded portions of a surface.  
  
If two or more sheets that need to be matched overlap one another considerably, then you can snip the sheets to bring their edges close enough to enable good matching. In such cases, snipping can provide an alternative to trimming.
  
This function works by modifying the topology and the geometry of the input sheet. The resulting surface is a new bounded surface with a modified control point structure.
  
To operate:
  
Select the face to be snipped.
  
Select the Bounding objects (these can be curves, strings of curves, and planes).
  
Specify the region to be kept.
  
Apply to accept the result or use one of the Refit methods to refit the newly created snipped surface and accept the result.
  
Why should I use it?
It is useful to use Snip Surface to cut or break a surface in cases where you expect to use the new surface as an input to another operation. As snipping modifies both the topology as well as the geometry of the new surface, it is possible to use it for options such as Match Edge and X-form.  
  
Snip Surface has proved useful for surface creation using the Control Point Edit method. Trimmed sheet does not provide this ability.  
  
The only limitation with Snip Surface is that, unlike a trimmed surface, a snipped surface cannot be unsnipped.  
  
Where do I find it?
Edit-> Free Form Features-> Snip Surface

Assembly Arrangements
What is it?
You can define assembly arrangements to specify alternative positions for one or more components in your part, and store those alternatives with your part. An arrangement determines:
  
The position and orientation of the immediate child components
  
The Variable Component Positioning (VCP) of any subcomponents
  
The Used arrangement for each immediate child component.
  
The system automatically creates an arrangement (and sets it as both the active and the default arrangement) when:
  
You have not created an arrangement by the time you add or create the first component in a new part.
  
You convert a pre-Unigraphics NX 2.0 part.
  
Two new arrangement-related columns in the Assembly Navigator are:
  
Arrangement -- this column specifies the Active arrangement for the displayed part. For each component in the assembly, it specifies the Used arrangement.
  
Arrangement Specific -- this column indicates whether the component is "arrangement specific," which means that you want to force edits to happen in that particular arrangement.
  
Several arrangement options are on the new Arrange cascade menu, which is located in two places: the graphics window pop-up menu and the Assembly Navigator pop-up menu. The Arrange cascade menu contains:
  
Arrange Position toggle -- if this is toggled OFF, you will receive a warning that arrangement-specific edits will be deleted for the selected components.
  
a list of arrangements in the part -- you can select one to make it active.
  
Edit Arrangements -- which brings up the arrangements dialog to let you edit arrangements in the selected components. This option is also located on the Assemblies-> Components menu.
  
Many arrangements can now be created and updated based on the loading of I-DEAS Assembly Configurations from .xpk files. When Unigraphics NX part files are loaded into I-DEAS, only the currently active arrangement is loaded into an I-DEAS Assembly Configuration.
  
Why should I use it?
Arrangements let you switch easily between different alternative component positions in your assembly. You can save as many arrangements as you need, which keeps you from having to individually specify the variable positions that you want to reference when you open your assembly.
  
Where do I find it?
Arrange (on the graphics window or Assembly Navigator pop-up menus)
  
Assemblies-> Components-> Edit Arrangements
  
   
  
  

Assembly Navigator Preview Panel
What is it?
The Assembly Navigator preview panel is an expandable area of the navigator that displays the stored preview of loaded or unloaded components. This helps you open the exact part that you need.
  
Open the Assembly Navigator and select any component. To view a preview, click the Preview banner displayed at the bottom or side of the navigator. You can leave the view expanded, and browse the assembly component-by-component.
  
Why should I use it?
When you are working with a large assembly, you can use the Preview panel to open only the parts that you need. This keeps the memory usage low for better performance.
  
You can also use the Preview panel to make sure that parts have reasonable previews, or to simply view the components in your assembly for better understanding.
  
Where do I find it?
At the bottom or side of the Assembly Navigator (which you open with the Assembly Navigator tab)
  
   
  
  

Assembly Navigator Dependency Browsing Panel
What is it?
The dependency browsing panel lets you view the dependencies in a selected object within your part or assembly. The panel, which is a special extension to the Assembly Navigator and the Part Navigator, replaces the Object Dependency Browser and the Information-> Feature functions.
  
The dependency panel handles components, parts, and assembly constraints for the Assembly Navigator.
  
Dependency information for the selected object's node includes:
  
Parents -- objects that the selected object depends on
  
Children -- objects that depend on the selected object, or objects generated by the selected object (such as members of an instance array)
  
You can click the Detailed View button to check relationships at the edge, curve, or assembly constraint level.
  
You can use the Forward and Back buttons to navigate between the dependencies of the most recently selected objects.
  
Why should I use it?
You can use it to analyze the potential impacts of a planned modification to your part or assembly.
  
Where do I find it?
At the bottom (or possibly the side) of the Assembly Navigator or the Part Navigator
  
   
  
  

Assembly Subsequences
What is it?
You can now create subsequences restricted to a particular group of components in an assembly.  
  
You can also refine a sequence step that assembles or disassembles a group of components in order to reference a particular sequence for that group.
  
Why should I use it?
You can use it when you need to create a sequence for a limited group of components within an assembly, rather than using all the components.
  
This functionality is also useful when you want to define one or more sequences within the context of a larger sequence.
  
Where do I find it?
In the Sequence Navigator, commands for subsequences are on the pop-up menu of a Step node that assembles or disassembles a group of components.
  
In the Assembly Navigator, you can create a sequence specific to a particular component group by using the pop-up menu on a Filter node (that contains those components) in the Filters in Part folder.
  
  

Deformable Components
What is it?
Deformable components have been enhanced in the following ways:
  
The lightweight reference set for components that have been promoted or deformed now displays a facet of the promoted or deformed geometry (rather than the original geometry, as previously).
  
You can now deform a component in an assembly when the deformable component and the assembly use different units. The units of the deformable component are automatically converted when you deform it. (You will receive a warning message before the conversion occurs.)
  
You can use the new Deformed Component Open API to automatically create deformed components.
  
Why should I use it?
The lightweight reference set can have significant performance improvements over more detailed reference sets (such as the model reference set). The other enhancements let you use deformable components in assemblies where you could not use them before, and increase the methods you can use to create them.
  
Where do I find it?
Tools-> Define Deformable Part
  
Assemblies-> Components-> Deform Part
  
   
  
  

Improved Display Property Synchronization
What is it?
When you use copy display properties from subassemblies to assemblies that use those subassemblies, the copied properties now include:
  
Materials
  
Textures
  
Individual object (such as a face) properties that will now be copied onto the corresponding assembly object
  
Previously, only colors, translucency, partial shading, layer settings, and attributes on components were copied.
  
Also, when you create a non-master part, display properties are now automatically synchronized from the master to the new non-master. Any objects that are blanked in the master will be blanked by default in the non-master, and the non-master is created with the same viewing direction and scale as the master. This lets the non-master match the appearance of the master as much as possible.
  
This is not supported for non-masters in UG/Manager or functions where non-masters are created automatically (such as template drag and drop).
  
Why should I use it?
When you copy display properties, more types of properties are now copied, increasing the synchronization between the original objects and the corresponding objects.
  
Where do I find it?
The Display button in the Synchronize Subassembly Properties section of the Assembly page in the Component Properties dialog